Configuring M660V Tool Diameter Data on the OSP 300M

The M660V with OSP 300M separates cutting compensation from descriptive tool-model data. Entering a value in radius geometry does not populate a visible tool-diameter attribute because that field belongs to the compensation system. Diameter, flute, and length attributes are associated with a tool model created or selected through Easy Model. Treat these as separate records during commissioning.

Tool-data field definitions

The term physical diameter here means the measured cutting diameter used to identify a tool. Radius geometry means the numerical geometry value used by cutter compensation. A tool model is the descriptive record that supplies modeled attributes such as diameter, flute information, and length.

Data item	Purpose	Wrong use	Commissioning test
Tool number	Identifies the tool requested by the machining program	Reusing one number for physically different tools without updating the associated records	Call the number and confirm that the intended assembly is selected
radius geometry	Supplies geometry for cutter compensation	Using it as a catalog-diameter field	Confirm that changing it affects the compensation record, not the tool-list description
Tool model	Stores modeled characteristics used for identification or graphical representation	Expecting blank model attributes to become editable without selecting or creating a model	Open the tool record and confirm that diameter, flute, and length data come from the selected model
Description or name	Provides a human-readable identifier where the screen supports it	Using descriptive text as the program's tool identity	Confirm the text remains associated with the intended tool number

Check 1: enter a controlled test value only in radius geometry. Expect the compensation value to change while the diameter shown by the model or tool list remains unchanged. Restore the production value after the test.

Tool-number and physical-tool assignment

Establish tool identity before adding model data. The NC program requests a tool number; the magazine record maps that identity to a loaded position; descriptive data help the operator recognize the assembly. A diameter displayed in a list does not replace this chain.

1. Assign one controlled tool number to the complete cutting assembly.
2. Record a short description that distinguishes diameter, tool type, and any holder-related characteristic needed during setup, if the control exposes a description field.
3. Match the tool number used by the CAM or NC program to the number stored at the machine.
4. Load the physical assembly and confirm its magazine assignment before attempting to improve the display.

A stable master tool-number system reduces ambiguity in a job shop. The documented example uses numbers from 1 through 999, with no tool repeated, and maintains the corresponding information in the CAM library and a spreadsheet. That workflow is optional, but the governing principle is sound: one number must resolve to one intended tool definition at the time a program runs.

Check 2: compare the setup list, program call, machine tool number, and loaded assembly. Expect the same identity at all four points before continuing.

Diameter entry through Easy Model

When the diameter, flute, and length cells request a tool-model file instead of accepting direct numeric entry, the control is treating those values as model properties. Create or select the model through Easy Model; do not force the cutting diameter into radius geometry to make the list look complete.

1. Open the tool record for the assigned tool number.
2. Invoke Easy Model or the available tool-model selection function.
3. Select an existing model only when its geometry matches the physical tool. Otherwise, create the required model with the measured tool characteristics.
4. Associate that model with the tool record.
5. Return to Tool Data and review the populated diameter, flute, and length attributes.
6. Enter or retain the required compensation geometry independently; derive it from the actual machining and compensation strategy, not from a desire to display the nominal diameter.

The measured cutting diameter is the deciding value when a nominal designation and the actual cutter differ. Read it from the tool presetter, measurement record, or qualified inspection method used by the shop. The control field must describe the physical assembly that is actually loaded.

Check 3: reopen the assigned tool after leaving Easy Model. Expect the selected model and its diameter-related data to remain attached to that tool number without altering the intended compensation value.

Magazine and Tool Data columns

Magazine Data and Tool Data serve different purposes. Magazine Data answers where a tool is loaded; Tool Data holds the identity, model, and machining-related records. A name or description column can appear only if that screen's display configuration offers the field. The existence of a description elsewhere in the control does not mean every list can expose it.

1. Open the column or display configuration available from Magazine Data.
2. Inspect the selectable fields for a tool name or description entry.
3. Repeat the inspection in Tool Data because its available columns may differ.
4. If the desired field is absent, retain identification in the tool record and use a controlled setup list as the magazine-facing reference.

Do not rename a tool number merely to improve sorting or list visibility. That practice breaks the relationship among CAM output, the NC program, stored compensation, and the physical assembly. If the screen cannot show the desired column, change the operating workflow rather than corrupting tool identity.

Check 4: leave and reopen each list after changing its display. Expect the selected column to remain visible and each row's text to correspond to the same tool number. If no name or description field is offered, treat that list layout as unavailable on the installed configuration.

Job-shop record control

Frequent tool turnover makes stale records more hazardous than missing display data. Use the control for active tool and compensation values, and keep a master record for the broader inventory when the built-in manager adds more maintenance than value.

Record	Controlled content	Update point
CAM tool library	Tool number and programmed geometry	When a reusable tool definition changes
Master list or spreadsheet	Tool number, description, and storage location	When inventory is added, rebuilt, or retired
Machine Tool Data	Active model, description, and compensation data	During setup and after measurement
Magazine record	Currently loaded tool assignment	At every load, unload, or transfer
Setup sheet	Tool numbers required by the job	When the program is released or revised

For a setup requiring tool numbers such as 7, 327, 19, 3, 667, and 752, verify each number against the master definition and then against the physical tool. A handwritten magazine note can assist an operator, but it must not become the authoritative mapping when the control record changes.

Check 5: perform a four-way comparison among the setup sheet, CAM definition, machine record, and physical tool. Expect no duplicate identity and no conflicting diameter description.

End-to-end commissioning verification

1. Select one tool whose physical diameter can be measured independently.
2. Confirm its unique tool number in the program and machine record.
3. Confirm that the associated Easy Model data describe the measured tool.
4. Confirm that radius geometry contains the intended compensation value rather than a copied catalog diameter.
5. Confirm the magazine assignment points to the loaded physical assembly.
6. Command the tool using the shop's normal setup procedure and verify the selected tool before permitting machining.
7. Run the approved prove-out method and inspect the resulting feature. If the feature is wrong, diagnose compensation, model assignment, program geometry, and physical-tool selection as separate variables.

Check 6: expect the commanded tool number, displayed tool identity, selected model, magazine assignment, and physical assembly to agree. Expect the inspected feature to respond to the compensation record, not to descriptive diameter data.

FAQ